Pausing at Nodes

I've been experiencing a problem the last few times that I've been cutting. I'm cutting out some large commerical signs with very simple/large letters. The last few jobs that I've done I've noticed that my machine slows down significantly at each node. Each letter has 4-8 nodes total depending on the letter. Even on arcs that are as smooth as can be (example: the letter "O") it will slow way down at each node. At first, I thought that it may be my cut rules slowing it down, so I tried it again without any cut rules, and it cut exactly the same. I have my following tolerance set at the standard .010" and it hasn't done this before. It just started a few weeks ago.

If you use the standard SheetCam postprocessor then it may be worth a try changing the following in the GCode file:

From:
To:

I'll give it a shot. Is there a way that I can take it out of the post so that I don't have to remove it from every gcode file? If not, that's fine too.

Sure, it is in the current postprocessor at line 72, it looks like: just change it so it looks the same.

Is this the spot that I need to change? Still having a lot of issues with it slowing down at a really small area that the table shouldn't have any issues keeping up the velocity in.

phillc54 wrote: Sure, it is in the current postprocessor at line 72, it looks like:

Code:

if scale == metric then post.Text (' G64 P0.254 Q0.025 (tracking tolerances: 0.254mm)\n') else post.Text (' G64 P0.01 Q0.001 (tracking tolerances: 0.01")\n') end

just change it so it looks the same.

I have revision F if that makes a difference

It seems to have been a sheetcam issue with import tolerances being too small!

CBEAR wrote: It seems to have been a sheetcam issue with import tolerances being too small!

Happy we finally got this figured out!!

To anyone following along, we changed this import setting in sheetcam:
from the default of 0.0004" to 0.010"

Per sheetcam manual:

Max detail reduction error
Some drawings consist of a large number of very small line segments (especially polyline curves converted to DXF). This can slow down processing and produce very large g-code files. It can also slow down machining. SheetCam tries to reduce the number of lines when it loads the drawing. Removing lines introduces small errors and this value is the maximum allowable error. For Plasma cutting you can afford to have quite a large error (say .020"). The setup wizard adjusts this value to suit.