Splines to Gcode from dxf file

Finally I can show some G5 code that actually runs in linuxCNC. Against my previous posts, the parameters I,J,P, Q are indeed given relatively to the start and end points. This should give a circle of Radius 10 mm:and this an ellipse of size 20x10 mm:
Details on github with some reorganization of the files.
github.com/Matttab/spline-examples/tree/main/linuxCNCsplineTest

if you have a spline in a DXF file there are normally a few options to change it to a simple entity (polyline) which is recognisable by post processing software.

I normally use "splineedit" if I am using AutoCAD / bricscad and only dealing with 1 spline, and convert it to a polyline entity, with a high curve fit number ( but you will end up with a lot of entities / segments).

option 2 if I have more than 1 spline..... I create a new linetype called "splines" or whatever and make it my current layer.  I then use "qselect" to select all spline entities and place them on their own layer I just created.  I then turn off all layers except the one I am working on via "-la" , "*", "off" 

I then used "pedit" (polyline edit) and "m" (multiple) and then select all the splines with a mouse sweep of the screen followed by selecting "splines to polylines" and again give it a high precision, and then save the file as a DXF for sheetcam / estlcam to post process to gcode.

I have also read that you can save the DXF as an old r12 DXF file format and it will do a similar thing as r12 DXF does not recognise splines and will convert them to polylines..... although I've just read this and not tried it out.

3d splines can be a pia as they have elevation, so if you have bricscad ot full autocad you can run commands such as "flatten" and "overkill" to flatten the objects to the same plane "Z0" and remove overlaid or multiple stacked entities one on top of each other.

librecad will do some of the above but I don't think it has overkill or flatten commands.

These G5 commands will give the following circle when loaded to linuxCNC. 

These G5 commands will give the following ellipse when loaded to linuxCNC. 

In axis you can go to File and next Proprieties (or gcode proprieties, can't remember the correct name ) and you can see the respective length of the Spline(s).

This value can be compared if matches the length of the Spline on CAD program. Its a quick way to confirm is its correct.

João

This is helpful, thanks for sharing.

Thank you for nice post.