identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
09 Jul 2019 11:00 #138943
by ahhkoch
Any idea if this is possible?
Motion.motion-type offers only values for linear and arc-feed.
But my goal is to activate some external hardware only when linuxcnc is doing a drill operation.
Any idea or Chance if and how this could be possible?
Thx!
Motion.motion-type offers only values for linear and arc-feed.
But my goal is to activate some external hardware only when linuxcnc is doing a drill operation.
Any idea or Chance if and how this could be possible?
Thx!
Please Log in or Create an account to join the conversation.
09 Jul 2019 13:38 #138950
by PCW
Replied by PCW on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
A somewhat clunky way would be to run the gcode through a filter and bracket the G83,G76 with M62/M63
Please Log in or Create an account to join the conversation.
09 Jul 2019 13:44 #138951
by ahhkoch
Replied by ahhkoch on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
I lke this idea because ist just a little postprocessor modification...
Thx for this!
Any other ideas?
Thx for this!
Any other ideas?
Please Log in or Create an account to join the conversation.
09 Jul 2019 15:52 #138959
by BigJohnT
Replied by BigJohnT on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
You can also make a filter to make the changes when you open the file.
linuxcnc.org/docs/2.7/html/config/ini-co...html#_filter_section
JT
linuxcnc.org/docs/2.7/html/config/ini-co...html#_filter_section
JT
Please Log in or Create an account to join the conversation.
10 Jul 2019 06:33 #138991
by ahhkoch
Replied by ahhkoch on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
Awesome! Great! Thx. The incredible flexibility of linuxcnc is sometimes too much "to see/know everything" 
Please Log in or Create an account to join the conversation.
12 Jul 2019 14:01 #139174
by andypugh
Replied by andypugh on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
Can the requirement be correlated to specific tools? If so then you could set HAL pins in a remap code, or possibly use halui.tool-number to pick from a mux.
Please Log in or Create an account to join the conversation.
12 Jul 2019 17:02 #139190
by ahhkoch
Replied by ahhkoch on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
Hi Andy.
unfortunately not. We do Drilling-Operations with different tools. Thatswhy i am fine with the solution now:
A Gcode filter adds before G81 a M62 P0 and after G80 a M63P0.
The triggered HAL-PIN is linked to my internal MIST-cooling solution
Works perfect for me...
Greetings
Andreas
unfortunately not. We do Drilling-Operations with different tools. Thatswhy i am fine with the solution now:
A Gcode filter adds before G81 a M62 P0 and after G80 a M63P0.
The triggered HAL-PIN is linked to my internal MIST-cooling solution
Works perfect for me...
Greetings
Andreas
Please Log in or Create an account to join the conversation.
15 Jul 2019 13:41 #139423
by andypugh
Replied by andypugh on topic identify in HAL when Linuxcnc is doing drilling operation (G83/G76...)
Glad you have it working.
But my suggestion with the mux would have worked for as many tools as it needed to, but the tool numbers that got special treatment would be hard-coded in the HAL file, in effect.
Another alternative would have been to add 100 to any tool number that needed the mist cooling, and then handle the differences in a remapped tool change file
O100 IF[ <_tool> GT 100]
M6 [<_tool> - 100]
M7
O100 ELSE
M6 <_tool>
M8
O100 ENDIF.
But my suggestion with the mux would have worked for as many tools as it needed to, but the tool numbers that got special treatment would be hard-coded in the HAL file, in effect.
Another alternative would have been to add 100 to any tool number that needed the mist cooling, and then handle the differences in a remapped tool change file
O100 IF[ <_tool> GT 100]
M6 [<_tool> - 100]
M7
O100 ELSE
M6 <_tool>
M8
O100 ENDIF.
Please Log in or Create an account to join the conversation.
Time to create page: 0.068 seconds